10: Machining assembly

Exercise 10: Machining assembly

Version compatibility

This exercise was carried out with version 27.0 (Vertex 2021).

In this exercise you will learn to

To make machinations in the assembly that are not visible in the parts of the assembly. Typically, such a situation is a structure welded from profiles, which is machined only after welding.

Functions to be used:

Importing a compressed model into a Vertex system.
Machining Features > Execute.
New Drawing for model.
Part numbering.
Properties of part > To Assembly Parts List.

Get a project that includes the necessary assembly

Download the Vertex project zip VXEN_PROF10.vxz here.
Drag the file from the downloads section of your Internet browser onto Vertex G4.
Be sure the models are found (in browser B) in project VX_COURSE_PROF.
- If necessary, refresh your browser, if those models VXEN_PROF10* are not found immediately.

Open the assembly model

Press the
button (B opens the universal browser of Vertex G4).
Select a project: VX_COURSE_PROF.
Open the model VXEN_PROF10.

The model has a SKELETON part, which is used to add four L-profiles to the model, and a part (VXEN_PROF10-P1) with has only machining tools.

Useful keyboard shortcuts

= Shows or hides auxiliary geometry (guide lines, cross sections, and auxiliary planes).

= Shows or hides the machining features, ie tool geometry.

Save the model to your own project

Function: File > Save as New.
Enter the ID.
Fill in the archive information.
Select the project where the model will be saved or create a new project.

Perform machining

Right-click function: Machining Features > Execute.
Hide the part that contained the machining tool (The M key also drives the same thing).

Machining Features

This function is ideal in cases where machining cannot be carried out before welding, ie parts cannot be machined separately.

In cases where the parts need to be machined before welding, it is advisable to use the Boolean function and select the action from there: Subtract with tool.

For example, when a drawing is made for parts, which must show all machining.

Create a drawing for the model

In the feature tree, click: Drawing.
Right-click function: New Drawing.

In the dialog New drawing, select data:

Scale: 1:2.5
Sheet: A3
Select projections: front and top.
Tangential lines: Draw as virtual shape lines (thin).
OK progresses to the archive data.

Add dimensions

Hole placement: (Dimensions group) Continuous baseline.
Hole diameter: Fast Dimensioning.

Add part numbers

Function: Parts List > Part number > Number.

Now you notice that both the machining tool (VXEN_PROF10-P1) and the SKELETON part are being added to the parts list.

Numbering should not be performed.
Press the Cancel.
Press the Cancel also in dialog Part Number.

Remove the SKELETON part from the part numbering parts

Activate the model window. For example, with the Ctrl Tab key combination.
Click on the SKELETON part.
Right-click function: Properties.
Deselec: To Assembly Parts List.

Remove the Tool part from the part numbering parts

Click on the tool part (VXEN_PROF10-P1).
Right-click function: Edit.
Right-click function: Properties.
Deselec: To Assembly Parts List.

Exit from part to assembly

OK.

Add part numbers

Open or activate the drawing.
Function: Parts List > Part number > Number.
Press Number.
OK (in Parts List dialog).
OK (in Parts Number dialog.
Click the highlighted part.
Click the location of the part number symbol.
Finish numbering the parts with a Done acknowledgment when both parts are numbered.
- or
  key, middle mouse button or right-click function

You can vary the models as needed

Both models have dimension variables.
You can vary the profiles directly in the assembly model because the dimension variables of the local part (SKELETON) are presented in it.
You can vary the part that contains the tools by editing the part model (VXEN_PROF10-P1).

Save the drawing

File > Save or click
or press

Save the model

File > Save or click
or press