12. Texts

Exercise 12: Texts in the part

Version compatibility

This exercise was carried out with version 27.0 (Vertex 2021).

Table of Contents

In this exercise you will learn to

To add texts to the part.
To mirror the texts to be added into the sketch.
To mirror the features.

Functions to be used:

Sketching: Two Point Rectangle, Acr with Tree Points and Text.
Sketching constraints: Distance, Symmetry and Radius.
Operations: Boss Extrusion and Cutout Boss Extrusion.
Part: Feature Mirroring.

Create a new part

File > New > Part.
- Enter the label (which is also the name of the model and by default will be the name of the drawing).
- Enter the archive information by clicking Arc.Data.
- Select the project for the model.
- OK.

Start sketching

New Sketch > To lateral (YZ) plane

Sketch the body

Function: Two point rectangle (Start at the origo)..
Function: Acr with Tree Points. (Without tangentiality).

Edit:

Top horizontal line properties: Construction line.

Constraints:

Dimension or Distance.
Radius.

Visualization of constraints

Dimension constraints are always displayed.
The symbols for other constraints are shown or hidden with the F9 key.

Perform the boss extrusion operation

Stop sketching (the green OK button).
Select: Boss and Extrude.
Select: Length or Angle.
Enter the value: 120.
Click OK.

Create a sketch on the front face

Click the face of the part.
Right-click function: New Sketch > Face,

Add text

Right-click function: Text (Add Text)
Enter text, e.g. VERTEX.

You can affect the height of the text with the Height field and the Scale field.

Enter 3.5 for height and 1:2 for scale or
Enter 7 for height and 1:1 for scale.

Place the text manually. (Text cannot be placed with constraints.)
Press Esc to stop entering text.

Text parameters height, scale and placement points

If the drawing is made on a scale of 1:1, then the height given here, e.g. 3.5mm, is shown as it is in the drawing.

If the drawing is made on a scale of 1:5 and you want the text to appear in the drawing at a height of 5 mm, it is advisable to give a height of 5 and a scale of 1:5 or a height of 25, with the scale remaining 1:1.

Also note the radio buttons around the Text box, which allows you to adjust the text hang points relative to the cursor.

Perform the cutout extrusion operation

Stop sketching (the green OK button).
Select: Cutout and Extrude.
Select: Length or Angle.
Enter the value: 2.
Click OK.

Add curved text to the end face of part

Click the end face and the Right-click function: New Sketch > To Face.

Add text, eg VERTEX

Height: 3.5
Scale: 1:2
Curvature: -50
Letter spacing: 0.5

Place the text.
Press Esc to stop entering text.

Perform the boss extrusion operation

Stop sketching (the green OK button).
Select: Boss and Extrude.
Select: Length or Angle.
Enter the value: 2.
Click OK.

Text parameters Curvature and Letter spacing

Curvature = Indicates the curvature of the center of the text.

A positive curvature produces a "Smile Face" curvature.
A negative curvature produces a "Sad face" curvature.

Letter spacing = The default value comes with an empty value.

A positive value increases the space between letters.
A negative letter spacing narrows the letter spacing or even reverses the order of the letters "from right to left to read."

The text parameters above in the attention box

1) Normal text (Width: 1 and Spacing: blank).

2) Letter Spacing 1 (and Width 1).

3) Width 2 (and Spacing: blank).

Extrude the text from the surface past

Right-click function: New Sketch > To horizontal (XY) plane
- Or if the auxiliary levels are visible, then to the face of the horizontal plane.

Add text, e.g. VERTEX

Height: 20
Scale: 1:1
Curvature: blank
Letter spacing: blank

Place the text.
Press Esc to stop entering text.

Perform the boss extrusion operation

Stop sketching (the green OK button).
Select: Boss and Extrude.
Select: To Selected Face
- Click the Face
Enter the value: 1.
Click OK.

Offset Value of extrusion

The positive offset value of the extrusion extends the extrusion to a face parallel to the clicked face, which is by an Offset value above the clicked face.

In this exercise, the extrusion starts moving in the middle of the part and extends by the surface + Offset past the surface.

If the sketching plane had been outside the part and the extrusion had been done on the selected surface with a positive offset value, then the extrusion would not have extended to the surface but remained "in the air" by the value of the offset.